# Crane pedestal analysis

• 130 Views
• Last Post 24 September 2018
• Topic Is Solved
thanhttdt posted this 14 September 2018

Hi everyone,

I do analysis for crane pedestal by using ansys, but I get some trouble while model and apply load. Could you please take a look and give me some advice

1. How to apply load SWL (safety working load)? I mean, is it necessary to model all crane's pedestal, crane's cabin, crane's boom and apply load at the top end of crane's boom Or we have another way to apply this load. Is remote force suitable to apply this load?

2. How to model a structure to act as a wire?

peteroznewman posted this 15 September 2018

Hello,

To analyze the pedestal of the crane, you have to model all the load carrying parts of the pedestal.

You can simplify the boom to a line body and mesh it with beam elements, just make sure the total mass of the boom equals the mass of the line body. You do this be defining a custom material and adjusting the density of that material until the mass of the line body equals the mass of the boom.

You don't have to model the cabin, only the structural plates that surround the cabin and carry the load.  You have to include the weight of all the non-structural parts in the pedestal. If you have an estimate for the weight of the cabin, you can add that as a Point Mass, supported by appropriate parts of the structure. The total mass of the model should equal the total mass of the crane. You can customize the density of Structural Steel to make up the missing mass in the total for the model when compared with the actual weight of the crane.

1. For the SWL, use a vertical force in Newtons of Mg  where M is the SWL in kg and g is 9.8 m/s^2

2. Use a Spring Element to represent the wire from the end of the boom to the top of the pedestal. You can estimate the spring rate from the wire properties, but it's not critical, it just affects how far the boom droops.

You have to turn on Standard Earth Gravity as a load in your model to have the weight of the parts be included.

Regards,

Peter

peteroznewman posted this 16 September 2018

You might benefit from watching a video on using mesh connections to put a sheet body model together.
It uses a Crane Boom example.

Below is a video on using springs as cables to support a boom.

thanhttdt posted this 18 September 2018

If I model the pedestal only and apply force like below, do you think that it can be the same like real working condition

I use fix support at A and B (as the connection between pedestal and decks)

Acceleration C is a gravity (self-weight of pedestal),

Foundation load D is the total cabin's load, I put this force at the red surface

Regarding to SWL, I change this position from the top end of crane's boom to the red surface, so that at the red surface there are a force F = SWL and the moment M = SWL*Boom_Length

For the weight of the boom, I will do the same as the SWL (I don't put it here)

As you said, wire just need when calculate the strength of boom, so I will neglect it in this case

Could you give me any comment

peteroznewman posted this 18 September 2018

Between the Pedestal and the Cabin/Boom-pivot assembly, there is a massive bearing to let the Cabin/Boom rotate about the Pedestal. I think you have correctly drawn the Free Body Diagram for the forces going into that bearing at the top of the pedestal if the winch that lifts the SWL is in the cabin. But if the winch is below deck and the cable goes down the center of the pedestal, then there is an additional down force of SWL. The pedestal has to support the SWL at the end of the boom AND the SWL tension in the cable.  If the winch is in the cabin, the tension in the cable is an internal force that does not add to the forces going through the bearing and into the pedestal.

If you want to limit your analysis to just the Pedestal, then when you include the down force of the mass of the boom and the moment for the distance to the boom center of gravity, you will have a representative load.

I expect high stress where the pedestal meets the two decks. You can consider moving the fixed support further away from the pedestal and modeling some of the connection between the pedestal and the two decks so the peak stress in the model is not at a fixed support.

Regards,

Peter

thanhttdt posted this 22 September 2018

Thanks for your support, I will seperate boom and calculate reaction force at the connection between boom and pedestal, and tensile force in the wire as well.

And as you mentioned, winches are stored in the cabin.

Do you think my analysis is ok?

peteroznewman posted this 22 September 2018

Those a good clean Free Body Diagrams. You will do sum of the moments about the boom pivot to solve for T_wire, and then sum of the forces in X and Y to solve for the R_boom force components. Your analysis is okay.

Regards,

Peter

thanhttdt posted this 24 September 2018

Thank you very much

Best Regards