Specifying a base acceleration at a revolute joint.

  • 48 Views
  • Last Post 08 October 2018
AndreaEnid posted this 13 September 2018

Hi! 

I want to assign a base acceleration at the base of a wall that have a rotational base constraint. I used a revolute joint to assing its stiffness. 

The base acceleration allows me to put the base acceleration only at fixed and displacements supports. I will appreciate any help.

 

Order By: Standard | Newest | Votes
peteroznewman posted this 13 September 2018

Hello AndreaEnid,

Base acceleration is used to simulate the input a structure might see in an earthquake or when sitting on a vibrating rigid surface like an engine block or a shaker table top.

Can you provide an image of the structure you are working on. I don't understand your "rotational base constraint". Do you mean you have a revolute joint that you added a spring to add rotational stiffness?

Regards,

Peter

AndreaEnid posted this 13 September 2018

The wall is the element at the left. The other big element is fixed at the base. The assigned revolute joint at the base of the wall is the one that appears in the tree at the left, below of Connection. I want to put an earthquake at the base of the wall and the other element. ANSYS allows me to put the base acceleration only to the fixed base, but I want to put the acceleration at the base of the wall too. 

AndreaEnid posted this 13 September 2018

peteroznewman posted this 13 September 2018

Is the yellow wall bonded to the large block?

If so, then just include the bottom of the wall as a Fixed Support. There is such a large mass and a long contact area that the revolute joint on the short edge on the bottom of the wall is going to be insignificant. Suppress the Revolute and add that edge to the Fixed Support.

AndreaEnid posted this 13 September 2018

Oh ok. Yes, the yellow wall is bonded to the large block. The problem is that I want to model the wall with a rotational constraint with a stiffness (I have the value), that is a important part of the model. And I need to put the acceleration at the base of the large block (soil) and the wall, but the program allowed me to put it only in the fixed one.

peteroznewman posted this 13 September 2018

Create a stand alone Transient Structural analysis system (not connected to Modal) and you can have your rotational joint and spring and apply the earthquake acceleration to all the mass in the model using an acceleration-time history load.

If the wall is supporting a block of soil, I'm not sure that Bonded Contact is appropriate. Wouldn't frictional contact be more appropriate? 

AndreaEnid posted this 18 September 2018

I already did that too, but in reality the amplitude of the earthquake is not the same in all the soil. I need to assign the acceleration as a base acceleration.

I am comparing different cases, and one of those cases is considering a Bonded Contact. 

peteroznewman posted this 18 September 2018

You could create a third rectangular block under the soil and the wall. Make that a rigid body and use either bonded or frictional contact to the soil. The rotational joint with its mobile side scoped to the base of the wall will now have its reference side scoped to the rigid body. Add a translational joint between the rigid body and ground and add an acceleration load to that new joint. Now you have base acceleration on the soil and the wall.

AndreaEnid posted this 24 September 2018

How can I assign acceleration at the translational joint? I am trying to do that but for base accelerations the program allows me to assign it on fixed support or on a displacement boundary condition.

peteroznewman posted this 24 September 2018

If you don't have a Modal analysis solution feeding into the setup of a Transient Structural analysis, then you can assign an acceleration to the translational joint.

If you do have a Modal analysis solution feeding into the setup of a Transient Structural analysis, then suppress or delete the Translational joint and load and use a Fixed Support on the bottom of the third rectangular block. Then you can use base accelerations.

AndreaEnid posted this 24 September 2018

I did the second option. When I choose the bottom of the third rectangular block to be fixed, it did not want to assign it. The image shows what happen when I want to assign the bottom to be fixed.  

I tried also the first option, but in that case the acceleration will be in all the bodies and I do not want that case.

 

peteroznewman posted this 24 September 2018

In the first option, when you apply an acceleration load to a translational joint, that is applying the acceleration to the linear translation of the joint. It is a motion input, not an inertial acceleration load that acts on all mass at the same time, but acts only to displace the joint.  If the soil acts like a very soft elastic body and is sitting on a rigid platform that suddenly accelerates upward, the bottom of the soil will move with the rigid rectangle in the first instant, while the soil at the top will have no motion.  That is very different than applying an inertial acceleration load where all the soil will experience the acceleration in the first instant.

In the second option, I forgot that you can't assign a Fixed Support to a Rigid body. Just keep the joint but change it to a Fixed joint.

AndreaEnid posted this 01 October 2018

Hi peteroznewman. I tried the option of assigning a translational joint at the bottom of the rigid element and a fixed joint between the soil and rigid element. Then, I applied the acceleration load at the translational joint. When I click solve, several minutes later the program stop with the next message.

 

 

I also tried using the fixed joint at the base of the rigid element, but using that option ANSYS does not allow me to apply the acceleration as an acceleration load to the joint and neither as a base acceleration.

AndreaEnid posted this 01 October 2018

 When I assign a translational joint - ground to surface body, the joint in that is in 'the ground' is considered fixed right? If that is true, can I assign to that 'fixed joint' an acceleration? I think the answer is no but I am curious anyway.

peteroznewman posted this 02 October 2018

Hello AndreaEnid,

A Joint consists of two Coordinate Systems with equations that limit the motion between them.  When the Joint is between a Body and Ground, the second coordinate system is fixed to ground.  If you don't want a body to move, you can define a Fixed Joint.  When you want a body to move along one axis, that is a Translational Joint.

I tried the option of assigning a translational joint at the bottom of the rigid element and a fixed joint between the soil and rigid element. Then, I applied the acceleration load at the translational joint. When I click solve, several minutes later the program stop with the next message.

There are lots of reasons why the solver can generate an unknown error. If you create a Workbench Project Archive .wbpz file, you can attach that to a post, then I can take a look at it.

Regards,

Peter

AndreaEnid posted this 08 October 2018

Hi! I am very thankul with your help. Next is a link sharing the model.

 

https://drive.google.com/file/d/1w30j9bSd3hq85Zdo7V8zTZZs1yva5Ux_/view?usp=sharing

 

Thank you again!!

Andrea

peteroznewman posted this 08 October 2018

What version of ANSYS are you using, 19.1 or some other version?

AndreaEnid posted this 08 October 2018

Yes, the version I am using is 19.1.

Close